At PCB Trace we know that any changes required late in the PCB design process can cost 10-100x more than during the design phase. Most of these late changes are caused by DFM or Design for Manufacturing mistakes. Fortunately, these can be easily avoided by engineers. If DFM is tackled in time, it can reduce expenditure on your boards by up to 15-20% and avoid any delays which could be weeks or months.
Typically, designers will perform a DRC to ensure the design meets their internal design rules. These rules will generally be generic or set in the CAD template. However, the fabricator will have their own rules based on their process. This includes minimum drill sizes, plating aspect ratio, and lamination press registration. A board could pass 100% of DRC rules but still fail to meet the fabricators rules.
DFM ensures that your design can be built, is clear and complete for the manufacturer. Below we have listed 15 specific issues that can be checked. We also provide solutions. These have been separated into 4 clear processes.
Process 1 – Mistakes Stalling the Quote
You may have:
- Data that does not match: Gerbers, Drill Files, Netlist and Drawing do not match. They have slight differences.
- Non-clear build specification: You have not specified your PCB material, copper weight, finish and quality class.
- Board outline that is unclear or conflicting: Your dimensions do not match or keepout areas and cutouts have not been clearly defined.
- Have asked for something the manufacturer cannot do: You have requested an exotic finish, high layer count or specific process.
Process 2 – Mistakes Causing Engineering Queries
You may have:
- Designed features smaller than the manufacturers minimum: Trace widths, Spacing and Drills are too small.
- Insufficient annular rings and hole to copper: This can cause breakouts.
- Via sizes that are not suitable for your board thickness: This causes unreliable plating due to high aspect ratio.
- Too tight tolerances: This can cause additional costs.
Process 3 – Mistakes Affecting Build
You may have specified:
- Unbalanced/ unrealistic layer stack: This causes warping, twisting and registration issues.
- Difficult to source or unusual materials: This can cause long procurement times.
- Impedance control has not been supported by a suitable buildable geometry.
Process 4 – Mistakes Only Found at Assembly
You may have:
Incorrect pad/footprint geometry. Incorrect land pattern, no thermal relief or incorrect paste/mask openings.
Missed solder mask/silkscreen details: Slivers, exposed pads or text on solderable areas.
Missed panelization, fiducials and tooling: Difficult to hold/align and separate.
15 Mistake Reference Table – DFM Checklist
Process 1 – Mistakes Stalling the Quote
| # | Mistake | What it Looks Like | Why it Causes Delay | How to Catch | Quick Fix |
| 1 | Inconsistent data | Number of Gerber layers does not match the drawing. Drill file contains drill tools not shown on the drill chart. Netlist does not match copper. | Fabricator cannot determine which source is correct, job will be put on hold until clarified. | Ensure all files have been loaded in a Gerber viewer. Compare to drawing and netlist. Note when files were exported. | Re-export all files from final version in one go. Include README stating what files are and version. |
| 2 | Unclear build specification | Notes state ‘standard finish’. No copper weight, material or IPC class. | Fabricator will need to guess or ask. Will delay quoting. | Walk-through build specification. Material, Thickness, Copper Weight, Finish, Mask Colour, Class, Layer Count. | Have a fixed section on your drawing. All information should be filled in for all releases. |
| 3 | Unclear or conflicting board outline | Outline has been drawn on multiple layers. Different shapes. No labels on cutouts. Dimensions do not add up. | Cannot program routing path and panel until true outline has been confirmed. | Ensure outline matches mechanical layer. Ensure dimensions match CAD model. | Ensure your outline is on one layer only. Closed shape. Add dimensioned drawing. |
| 4 | Asking for something they cannot do | Exotic finish, very high layer count or special process has been requested without confirmation. | Job will be rejected or sent to alternative vendor. Quote process will start from the beginning. | Ensure each line of your specification matches the manufacturer’s capability sheet. | Confirm capabilities in writing before layout. Have a capability sheet for each vendor. |
Process 2 – Mistakes Causing Engineering Queries
| # | Mistake | What it Looks Like | Why it Causes Delay | How to Catch | Quick Fix |
| 5 | Too small features | Traces, spacing and drilling is too small. Often seen on BGA fanout. | Engineer will need to ask for a redesign or approve risk to yield. | Load fabricator rules into your DRC. Run before release. | Increase feature sizes. Only use tighter capabilities if required. |
| 6 | Thin annular rings and tight hole to copper. | Pad sizes are just larger than drill size. Copper is close to drilled holes. | Drill drift can cause breakout. Shop will flag a reliability issue. | Use fabricator drill tolerance in DRC to check annular ring. | Increase pad size or reduce drill size. Add teardrops where applicable. |
| 7 | Via sizes not suitable for board thickness. | Very small drill sizes on a thick board. High aspect ratio. | Unreliable plating. Will cause a query or surcharge. | Calculate board thickness ÷ Drill Size for all via sizes. | Increase via size, reduce board thickness or use blind/buried vias if justified. |
| 8 | Too close to edges/slots/cutouts. | Copper or traces close to board edge. No clearance around routed slots. | Routing tolerances can cause copper to show or short. | Ensure copper to outline clearance in DRC. Check visually. | Reduce copper to match fabricator edge clearance. Add keepout zones to all layers. |
| 9 | Too tight tolerances. | All dimensions have the tightest tolerance. Even non critical. | Unusual tolerances require special processes and extra review. | Check all dimensions with tolerance. Are they affecting fit or function? | Only apply tight tolerances to critical features. Use fabricator standard tolerance. |
Process 3 – Mistakes Affecting Build
| # | Mistake | What it Looks Like | Why it Causes Delay | How to Catch | Quick Fix |
| 10 | Unbalanced/ unrealistic stackup. | Large imbalance in copper. Dielectrics not in stock. | Risk of warping and twisting. Shop will need to suggest alternative stackup. | Ensure copper is balanced for each layer pair. Ask for standard stackup. | Use fabricator proven stackup. Symmetrical layers around center. |
| 11 | Difficult to source/ unusual materials. | Niche laminate or specific brand. No alternatives. | Long procurement time. | Check with fabricator before finalizing. Look for or equivalent. | Define your materials by performance (Tg, Dk, Df). Allow for equivalents. |
| 12 | Impedance control with no buildable geometry. | Impedance target has been stated but no layer, trace width or tolerance. Geometry not achievable with stackup. | Fabricator will need to recalculate. May need to change trace widths. Requires your approval. | Use field solver with fabricator actual stackup. Confirm which traces are controlled. | List controlled nets, target, tolerance and reference layers. |
Process 4 – Mistakes Only Found at Assembly
| # | Mistake | What it Looks Like | Why it Causes Delay | How to Catch | Quick Fix |
| 13 | Incorrect pad/footprint geometry. | Incorrect land pattern. No thermal relief. Incorrect paste/mask openings. | Assembly house will stop to confirm. Boards returned with soldering issues. | Check each footprint matches manufacturers recommended land pattern. Print 1:1 and trial fit parts. | Use verified library parts. Get a second person to review new footprints. |
| 14 | Missed solder mask/silkscreen. | Slivers between fine pitch pads. Text over pads/vias. | Fabricator will remove/change features or ask for approval. Extra review. | Use DFM software to check for slivers and text over pads. | Ensure mask expansion rules match fabricator minimum web. Remove mask from exposed copper. |
| 15 | No panelization, fiducials or tooling. | No fiducials, tooling holes, rails or depanelisation. | Cannot hold/align boards. Panel needs to be redesigned. | Check panel requirements with assembly house. | Add global and local fiducials, tooling holes and defined depanelization (tabs/V-score). |
How to add DFM to your workflow
DFM can be easily added to your workflow by:
- Including fabricator rules in your CAD design rules.
- Automated DFM analysis before every release.
- Quick peer review with sign-off.
- Keep a log of previous engineer queries. Turn repeat offenders into new rules.
- Speak to your fabricator before locking your layout.
Quick Reference
Below is a one-page pass/fail checklist for all 15 items:
DFM Pre-Release Checklist
15 checks to do before sending to fabrication.
| # | Check | Pass | Fail | Notes |
| 1 | All files (gerbers, drill, netlist, drawing) exported from final version. All files match. | ☐ | ☐ | |
| 2 | Build specification complete. Material, Thickness, Copper Weight, Finish, Mask Colour, Quality Class, Layer Count. | ☐ | ☐ | |
| 3 | Board outline on one layer. Closed shape. Cutouts dimensioned. | ☐ | ☐ | |
| 4 | All special requirements confirmed against fabricator capability sheet. | ☐ | ☐ | |
| 5 | Trace width, spacing and drilling meets fabricator minimums. | ☐ | ☐ | |
| 6 | Annular rings and hole to copper can withstand using fabricator drill tolerance. | ☐ | ☐ | |
| 7 | Board thickness / Drill Size does not exceed plating aspect ratio for all via sizes. | ☐ | ☐ | |
| 8 | Copper to edge and slots/cutouts meet fabricator rules on all layers. | ☐ | ☐ | |
| 9 | Tight tolerances only applied to critical features. | ☐ | ☐ | |
| 10 | Symmetrical stackup. Balanced copper. Based on fabricator standard build. | ☐ | ☐ | |
| 11 | Materials defined by performance (Tg, Dk, Df). Or equivalent. | ☐ | ☐ | |
| 12 | Controlled nets, target impedance, tolerance and reference layers listed. | ☐ | ☐ | |
| 13 | All footprints match manufacturers recommended land pattern. | ☐ | ☐ | |
| 14 | No mask slivers below fabricator minimum web. No mask on exposed copper. | ☐ | ☐ | |
| 15 | Fiducials, tooling holes, rails and depanelisation defined. | ☐ | ☐ |
Total: ______ / 15 Pass. Make sure you resolve all Fail.
Sign Off
| Field | Entry |
| Project / Board name | |
| Revision | |
| Target fabricator | |
| Designer (name / date) | |
| Reviewer (name / date) | |
| Approved for release | ☐ Yes ☐ No |
| Actions / Comments |
Conclusion
At PCB Trace we understand there are a few consistent errors causing delays. Fortunately, by incorporating DFM into your workflow and using a checklist you can easily overcome these delays and reduce the back and forth with the fab house.
Next time you have a release, use our checklist and ask for early DFM review.